PCB CNC: Unterschied zwischen den Versionen
|Zeile 205:||Zeile 205:|
Version vom 26. Juli 2010, 12:52 Uhr
CNCs can facilitate in the creation of PCBS:
- Manual etching and then using CNC to drill automatically.
- Cutting out the board , to have round PCBs, or similar.
- Automated isolation routing: From a PCB some surface parts are milled away, so that the connection copper area are left isolated.
Currently, all three steps are working on the Geilomat.
For the isolation, there is the normal approach, where all contours of copper areas are milled.
However much faster results can be obtained by milling the minimal path necessary to create the PCB-topology.
For a complete, dense EuroPCB, expect about one hour of total time:
- 10 minutes for preperation, mounting and setup.
- 15 minutes for drilling/cutting.
- 20 minutes for the isolation of the bottom layer.
- 5 minutes for flipping/remounting/aligning
- 20 minutes for the top isolation
- 10 minutes for manual overworking the board.
For an arduino shield, expect about 35 minutes:
- 10 minutes for preperation, mounting and setup.
- 5 minutes for drilling/cutting.
- 5 minutes for the isolation of the bottom layer.
- 5 minutes for flipping/remounting/aligning
- 5 minutes for the top isolation
- 5 minutes for manual overworking the board.
- Quite Faster than manual UV-exposing, etching and drilling.
- No chemicals
- Good for high currents, as wired are wide.
- Cheaper PCB material. (Same area approx 50% the price)
- PCBs of up to 30x20 cm. However, flatness is problematic.
- If the board is not mounted completely flat, the isolation might be not deep enough, and hence there are short circuits.
- Sometimes, flakes of copper short circuit neighboring copper areas. Usually at corners. A knife helps.
- Capacity between adjacent copper areas.
- Hotter soldering is required, as there are no thermal pads.
- 0805 SMD resistors work fine, although the solder locations are not visible any more. However, SMD chips are probably to small
Metaboard is a bash shell script, that will automatically create cnc-paths in the form of gcode files. The starting point is the eagle .brd file. It calls a couple of external programs:
- Eagle: to output the gerber files of the top and bottom layer
- eagle: to call an ulp-program "drillbernhard.ulp" that outputs the drilling and cutting paths.
- Visolate: To create the isolation paths.
- grecode To mirror the board for second side. (Grecode was created especially for metaboard.sh by --Bkubicek 09:55, 26. Jul. 2010 (CEST))
While these are called, a couple of windows will pop up and hopefully disappear again.
- Eagle sometimes stays on top: just close the opened .brd, and load your .brd again using the menu. If have no clue why this happens.
- It might be necessary to have a parent project file in the same directory?
The workflow splits into the following points:
- Preperation: create an eagle brd file, copy it
- Metaboard.sh: create the gcode files for the geilomat
- Setup: mount the board in the geilomat, insert a suitable mill head.
- EMC-setup: home the machine, "touch off"/set coordinate system so milling will be on the actual board
- Bottom layer:
- drilling and cutting
For single sided boards, the process stops here.
- Flipping the board, mounting it.
- Top layer:
- Loading the top layer debugging file.
- Aligning: Rotate and shift the top layers using grecode, so that the new gocde matches the mounted board.
- Isolate the top.
Create yourself a directory in ~/gcodes/ and copy your .brd file there. Then open up a shell window, move to the directory call
If all goes well, you will obtain a lot of *.ngc files, that contain [Gcode] for the CNC process. Also, a tmp directory will be created, where there are even more files. The files in the original directoy are:
- xxx_top.ngc: The top layer isloation paths.
- xxx_bottom.ngc: The bottom layer isloation paths.
- xxx_drillcuttop.ngc: The top layer drilling and cutting.
- xxx_drillcutbottom.ngc: The bottom layer drilling and cutting.
- xxx_debug.ngc: A file so you can view the content of all the other files at once, to check for errors, or measure coordinates..
Then you start linuxcnc.org/ EMC on the computer next to the geilomat. You load the xxx_debug.ngc file and look at it really intense to see weather it is correct.
Then you press the home-all bottom, and the mill will move to its home position on the close left corner in front of you.
Mount the board using the thin double sided tape and stick it to the flat-milled piece of wood.
You want to insert a 0.8 mm mill-head in the Kress (a drill might break in the the sidewards cutting movement). Then you move to one location just above the mounted PCB, and set the working coordinate system using "touch off" in X and Y. For the Z, you move next to the PCB, and go tiny bit deeper than the lower board edge, and touch off at the lowest z-coordinate value, which should be -2.5 mm. For security, move up so that the mill can move freely thereafter.
Load the xxx_bottomdrillcut.ngc file.
For the drilling, set the Kress to speed "5".
Close the geilomat-latch. Turn the spindle on in EMC so that the Kress rotates. Press the play button and watch out for problems. Stop with the Stop button, or with F1. After an emergency off with F1, you maybe have to reposition the machine. Try not to be overwhelmed by all the noise and awesomeness.
After the drilling and cutting has finished, move the mill so you can change the mill-head to a 0.1mm-0.3mm 30°-45° "Gravierstichel".Then, right next to the side of the board, or onto an hole, and touch off Z so that zero is ~0.3mm underneath the surface. Check the flatness of the board, and if there are problems, move deeper into the board.
Load the xxx_bottom.ngc file. Isolate the bottom.
Then remove the board, remove the sticky tape, and clean the surface a bit. Mount a new batch of tape to the milled surface, and glue it onto the wood so that you see the to-be top layer.
load the xxx_debug file. Define two positions on the board that you identify both on the mounted board and the in the software. Only drill holes or cut-corners on the flipped top surface are suitable ! Read the coordinates of this points in EMC by clicking at the line and reading the X-Y coordiates in the gcode-text-view. Write them down.
Move the mill to the same locations, and write down the coordinates displayed in the 3d-window.
Open a konsole, call with the inserted coordinates:
grecode xxx_top.ngc -o xxx_topnew.ngc -overlay physicalPointAx physicalPointAy physicalPointBx physicalPointBy GcodePointAx GcodePointAy GcodePointBx GcodePointBy
This will produce a shift-rotated gcode file xxx_topnew.ngc. Touch off the Z-height to a suitable value. Load xxx_topnew.ngc and isolate the top.
Metaboard background info
This is the manual workflow, that is now obsolete as most steps are done by metaboard.sh.
The PCB have to be put on a plain-milled surface of at least 3 mm thickness, as we are drilling. The slightest bend (0.2 mm) in the PCB will probably move the "Gravierstichel" out of the plane where it would isolate. You need a 0.6 or 0.8 mm drill with a mounting diameter suitable for the Kress-"Spannzange", probably 3mm or 1/8 inch=3.1something.
We will create three ngc-files, one for the isolation, one for the drilling, and one for the final cutting. They will be glued together in one ngc file to align them graphically using Axis.
- download Visolate
- On Windows, that is
- create a shortcut, respecting your paths, with the target ""C:\Program Files (x86)\Java\jre1.6.0_07\bin\java.exe" -Xmx1024000000 -jar C:\Users\bkubicek\Visolate.jar" and the working directory "C:/Users/bkubicek/Documents/eagle/LEDlampe/"
- download and install [java3d]
- save Datei:Drillbernhard.ulp.txt into your eagle/ulp directory without the .txt extension. Its an ugly hack of the next original ulp...
- save Datei:Gcode.ulp.txt into your eagle/ulp directory without the .txt extension.
- Create the Eagle board. Route only on Bottom Layer.
- Output using the cam-processor, using the "GERBER_RS274" device, and only the layers "bottom","pads", "vias". Filename gerber_boardname.
- Output using File->RUN->(ulp-directory)->drillbernhard.ulp . Layer "bottom", Mill and cut deaktivated, drill active,outputfile "drill_boardname.ngc"
- Output using File->RUN->(ulp-directory)->gcode.ulp . Layer "bottom", Mill and drill deaktivated, cut active,outputfile "cut_boardname.ngc", other parameters are nearly irrelevant.
- Then start Visolate, load the gerber file, make if full screen. press Fit. Fix Topology. Make toolpaths. Output file as "isolate_boardname.ngc"
- Then comes the joining of the three ngc files: Create a new ngc file starting with
M8 ; turn on spindle ; adjust to your mill F450 G90 G21 G0 Z2.54 ; move up to 0.1 inch above G0 X-0.24 Y-0.24 ;change this to align the drill holes with the the isolation path G20 ;; end head
then add the content of isolate_boardname.ngc without the m5 m3 tail. The isolation has relative coordinates, so we have to set a proper starting location via the previous head. Also, moving to the assumed Z=0 position would already mill the board, so we have to change the first Z move. comment out the first move to Z-0.01 it could look something like this
G20 G17 G40 G49 G80 G91 G1 Z0.1 G0 X0.10814 Y0.28534 ;G1 Z-0.1 ;; uncommented t G1 X0.00392 Y0 ;; end isolate
insert a commented line with an end program.
; G0 Z20 M2 ; program end to manual tool-change to drill
after the isolation we will insert the content of drill_boardname.ngc adjust the variables posdown to -2.1 posup to 1, feedown to 100,feedup to 200 after the cutting, create some blank lines and insert a section of cut_boardname.ngc, namely the part between (Start cutting wires) and (finished). This movements cut out the pcb from the surrounding. Maybe you have to invert all Y coordinates because of the mirroring
The complete file then should have some head, the isolation, the drilling and the cutting.
- Open this ngc file in axis, and adjust the relative position of the drills to the isolation by the G0 X Y in the head, saving and reloading in axis.
- Check if whether the board is in a right orientation or if it needs to be mirrored. This can be achieved by my gcode -filters: http://www.linuxcnc.org/images/fbfiles/files/grecode.zip , see also this forum post
- after all is good, remove the commend right before the drilling, to have the the program stop there. Reload in axis. Insert a 30 Degree 0.1 or 0.2 mm "Gravierstichel", home the machine, touch off at a suitable location, and start the program.
- If the isolation is not deep enough, touch off z in lower height, and restart.
Then Change to a 0.6 mm drill with a 3.12mm 1/8 inch holing diameter, touch of Z again, and re-insert the comment right before the drilling.
- Reload in Axis, scroll to the line right before the drilling, right click->run from here.
- do all the drilling and sidewards cutting.
- if you really want things to be perfect, you could locate the most outwards line in the isolation, and move them deeper Z-0.1 ->Z-0.12 and the following relative up-movent as well Z0.1 ->Z0.12. By that, there will be no copper close to the cutting locations.